HEIDENHAIN iTNC 530 (60642x-04) Cycle programming - Manual (Page 272)

272 Fixed Cycles: Multipass Milling
1
0
.5 F
A
CE MILLING (Cy
c
le 232, DIN/ISO:
G232)
 1st side length Q218 (incremental): Length of the
surface to be machined in the reference axis of the
working plane. Use the algebraic sign to specify the
direction of the first milling path in reference to the
starting point in the 1st axis
. Input range
-99999.9999 to 99999.9999
 2nd side length Q219 (incremental): Length of the
surface to be machined in the minor axis of the
working plane. Use the algebraic sign to specify the
direction of the first stepover in reference to the
starting point in the 2nd axis
. Input range
-99999.9999 to 99999.9999
 Maximum plunging depth Q202 (incremental):
Maximum amount that the tool is advanced each
time. The TNC calculates the actual plunging depth
from the difference between the end point and
starting point of the tool axis (taking the finishing
allowance into account), so that uniform plunging
depths are used each time. Input range 0 to
99999.9999
 Allowance for floor Q369 (incremental): Distance
used for the last infeed. Input range 0 to 99999.9999
 Max. path overlap factor Q370: Maximum stepover
factor k. The TNC calculates the actual stepover from
the second side length (Q219) and the tool radius so
that a constant stepover is used for machining. If you
have entered a radius R2 in the tool table (e.g. tooth
radius when using a face-milling cutter), the TNC
reduces the stepover accordingly. Input range 0.1 to
1.9999; alternatively PREDEF
X
Z
Q202
Q200
Q204
Q369
X
Y
Q357
Q253
Q207
k