HEIDENHAIN TNC 320 (340 55x-04) Cycle programming - Manual (Page 62)

62 Fixed Cycles: Drilling
3.3 DRILLING (Cy
c
le 20
0)
Cycle parameters
U Setup clearance Q200 (incremental): Distance
between tool tip and workpiece surface. Enter a
positive value. Input range 0 to 99999.9999
U Depth Q201 (incremental): Distance between
workpiece surface and bottom of hole (tip of drill
taper). Input range: –99999.9999 to 99999.9999
U Feed rate for plunging Q206: Traversing speed of
the tool during drilling in mm/min. Input range: 0 to
99999.999; alternatively FAUTO, FU.
U Plunging depth Q202 (incremental): Infeed per cut.
Input range 0 to 99999.9999. The depth does not
have to be a multiple of the plunging depth. The TNC
will go to depth in one movement if:
„ the plunging depth is equal to the depth
„ the plunging depth is greater than the depth
U Dwell time at top Q210: Time in seconds that the
tool remains at setup clearance after having been
retracted from the hole for chip release. Input range
0 to 3600.0000
U Workpiece surface coordinate Q203 (absolute):
Coordinate of the workpiece surface. Input range:
-99999.9999 to 99999.9999
U 2nd setup clearance Q204 (incremental): Coordinate
in the spindle axis at which no collision between tool
and workpiece (fixtures) can occur. Input range 0 to
99999.9999
U Dwell time at depth Q211: Time in seconds that the
tool remains at the hole bottom. Input range 0 to
3600.0000
Example: NC blocks
11 CYCL DEF 200 DRILLING
Q200=2 ;SETUP CLEARANCE
Q201=-15 ;DEPTH
Q206=250 ;FEED RATE FOR PLNGNG
Q202=5 ;PLUNGING DEPTH
Q210=0 ;DWELL TIME AT TOP
Q203=+20 ;SURFACE COORDINATE
Q204=100 ;2ND SETUP CLEARANCE
Q211=0.1 ;DWELL TIME AT DEPTH
12 L X+30 Y+20 FMAX M3
13 CYCL CALL
14 L X+80 Y+50 FMAX M99
X
Z
Q200
Q201
Q206
Q202
Q210
Q203
Q204
30
X
Y
20
80
50