HEIDENHAIN TNC 310 (286 140) - Manual (Page 167)

155 HEIDENHAIN TNC 310
9.5 Programming Examples
Example: Groups of holes
Program sequence
■ Approach the groups of holes in the main
program
■ Call the group of holes (subprogram 1)
■ Program the group of holes only once in
subprogram 1
0 BEGIN PGM UP1 MM
1 BLK FORM 0.1 Z X+0 Y+0 Z-20
2 BLK FORM 0.2 X+100 Y+100 Z+0
3 TOOL DEF 1 L+0 R+2.5
4 TOOL CALL 1 Z S5000
5 L Z+250 R0 F MAX
6 CYCL DEF 200 DRILLING
Q200=2 ;SET-UP CLEARANCE
Q201=-10 ;DEPTH
Q206=250 ;FEED RATE FOR PLUNGING
Q202=5 ;PLUNGING DEPTH
Q210=0 ;DWELL TIME AT TOP
Q203=+0 ;SURFACE COORDINATE
Q204=10 ;2ND SET-UP CLEARANCE
7 L X+15 Y+10 R0 F MAX M3
8 CALL LBL 1
9 L X+45 Y+60 R0 F MAX
10 CALL LBL 1
11 L X+75 Y+10 R0 F MAX
12 CALL LBL 1
13 L Z+250 R0 F MAX M2
Define the tool
Tool call
Retract the tool
Cycle definition: drilling
Move to starting point for group 1
Call the subprogram for the group
Move to starting point for group 2
Call the subprogram for the group
Move to starting point for group 3
Call the subprogram for the group
End of main program
X
Y
15
60
100
100
75
10
45
20
20
5