HEIDENHAIN TNC 310 (286 140) - Manual (Page 95)

83 HEIDENHAIN TNC 310
Example: Linear movement with polar coordinates
Define the workpiece blank
Define the tool
tool call
Define the datum for polar coordinates
Retract the tool
Pre-position the tool
Move to working depth
Approach the contour at point 1
Tangential approach to circle with R=1 mm
Move to point 2
Move to point 3
Move to point 4
Move to point 5
Move to point 6
Move to point 1
Tangential departure from circle with R=1 mm
Retract tool in the working plane
Retract tool in the spindle axis, end of program
0 BEGIN PGM 40 MM
1 BLK FORM 0.1 Z X+0 Y+0 Z-20
2 BLK FORM 0.2 X+100 Y+100 Z+0
3 TOOL DEF 1 L+0 R+7.5
4 TOOL CALL 1 Z S4000
5 CC X+50 Y+50
6 L Z+250 R0 F MAX
7 LP PR+60 PA+180 R0 F MAX
8 L Z-5 R0 F1000 M3
9 LP PR+45 PA+180 RL F250
10 RND R1
11 LP PA+120
12 LP PA+60
13 LP PA+0
14 LP PA-60
15 LP PA-120
16 LP PA+180
17 RND R1
18 LP PR+60 PA+180 R0 F1000
19 L Z+250 R0 F MAX M2
20 END PGM 40 MM
X
Y
50 100
50
CC
5
100
R45
60°
5
6.5 P
ath Cont
ours
—
P
olar Coor
dinat
es