HEIDENHAIN CNC Pilot 4290 - Manual (Page 133)

HEIDENHAIN CNC PILOT 4290 121
Linking tool dimensions G710
When a T command is programmed, the CNC PILOT replaces the
previous tool dimensions with new tool dimensions. When you
activate the adding function with ”G710 Q1”, the dimensions of the
new tool are added to the dimensions of the previous tool.
Parameters
Q:
Add tool dimensions
■ Q=0: Off
■ Q=1: On
Example of ”adding tool dimensions”
Rotating gripper
Stationary tools on tool carrier 2
Roughing tool for rear-face machining
Insert rotating gripper
Transfer workpiece from spindle to rotating
gripper (expert program)
Add tool dimensions
Add the dimensions of the rotating gripper and the
stationary tool
. . .
REVOLVER 1 [TURRET]
. . .
T14 ID”SETUP PICKUP”
. . .
REVOLVER 2 [TURRET]
T2001 ID“116-80-080.1“
. . .
BEARBEITUNG [MACHINING]
. . .
N100 T14
N101 L“EXGRIF“ V1
N102 G710 Q1
N103 T2001
. . .
Compensate right tool tip G150
Compensate left tool tip G151
Defines the tool reference point for recessing and button tools.
■ G150: Reference point of the right tool tip
■ G151: Reference point of the left tool tip
G150/G151 is effective from the block in which it is programmed and
remains in effect up to
■ The next tool change
■ The end of the program
■ The displayed actual values always refer to the tool tip
defined in the tool data.
■ If you use TRC, after G150/G151 you must also adjust
G41/G42.
4.6 Machining Commands
Example for application
For full-surface machining, the workpiece is
transferred to a rotating gripper after having been
machined on the front face. The rear side is machined
by stationary tools. To do this, the dimensions of the
rotating gripper are added to the dimensions of the
stationary tool.