Rockwell Automation 8520-MUM 9/Series CNC Mill Operation and Programming Manual Documentation Set User Manual
Page 294
Introduction to Programming
Chapter 10
10-20
Table 10.B
Word Formats and Descriptions
Address
Valid Range Inch
Valid Range Metric
Function
A
8.6
8.5
Rotary axis about X (AMP assigned)
3.3
3.3
Angle in QuickPath Plus programming
B
8.6
8.5
Rotary axis about Y (AMP assigned)
3.0
3.0
Second miscellaneous function (AMP assigned)
C
8.6
8.5
Rotary axis about Z (AMP assigned)
8.6
8.5
Chamfer length in QuickPath Plus programming
D
3.0
3.0
Tool radius compensation number
8.6
8.5
Fixed cycle parameter.
E
2.6
3.7
Thread lead
F
8.6
8.5
Feedrate function (F--word)
G
2.1
2.1
Preparatory function (G--code)
H
6.0
6.0
Tool length offset number
8.6
8.5
Parameter for probing cycles.
I
8.6
8.5
X arc center in circular interpolation
8.6
8.5
X lead in helical interpolation
8.6
8.5
Parameter in fixed cycles (AMP assigned)
8.6
8.5
Exit move vector in cutter compensation
J
8.6
8.5
Y arc center in circular interpolation
8.6
8.5
Y lead in helical interpolation
8.6
8.5
Parameter in fixed cycles (AMP assigned)
8.6
8.5
Exit move vector in cutter compensation
K
8.6
8.5
Z arc center in circular interpolation
8.6
8.5
Parameter in fixed cycles (AMP assigned)
8.6
8.5
Exit move vector in cutter compensation
L
3.0
3.0
Number of repetitions
M
3.0*
3.0*
Miscellaneous function
N
5.0
5.0
Sequence number
O
5.0
5.0
Program name
P
5.0
5.0
Subprogram name
5.3
5.3
Length of dwell in G04 and fixed cycles
Q
8.6
8.5
Parameter in fixed cycles
R
8.6
8.5
Arc radius
8.6
8.5
Return point in fixed cycles
8.6
8.5
QuickPath Plus radius designation
* Some of the system basic M--codes are 3.1 format however all system installer defined M--codes must remain 3.0. See Table 10.F on page for details.