Rockwell Automation 8520-MUM 9/Series CNC Mill Operation and Programming Manual Documentation Set - Manual (Page 659)

Milling Fixed Cycles
Chapter 26
26-27
In the G84.1 right-hand solid-tapping cycle, the control moves the axes in
this manner:
1. The tool rapids to the tapping position above the hole location.
2. The threading tool then rapids to the R point.
3. The control either orients or stops the spindle.
If a Q-word was programmed: the control:
yes orients the spindle
no stops the spindle
4. Tap-in: The clockwise rotation of the spindle ramps up to the
programmed S spindle speed and linear motion of the Z axis moves
synchronously to reach the Z position.
5. Tap-out: The spindle and linear motion reverse to the
counterclockwise direction and retract to the R point.
The tap-out speed is determined by F
*
S unless you programmed D
(tap-out rpm), in which case tap-out speed is F
*
D.
At the R point, spindle rotation has ramped to zero.
6. With G98 active, the cutting tool then accelerates to the rapid feedrate
and retracts to the initial point level.
With G99 active, the cutting tool remains at R point; no movement
occurs.
In single-block mode, the control stops axis motion after phases 1, 2, 3,
and 6 of the cycle (Figure 27.M2).
Important: When it is active, S--Curve Acc/Dec (G47.1) will be applied to
the rapid feedrate portions of the solid--tapping cycle.