Rockwell Automation 8520-GUM 9/Series CNC Grinder Operation and Programming Manual Documentation Set - Manual (Page 467)

Tool Control Functions
Chapter 13
13-5
You can enter data in the wheel geometry table and radius/orientation
offset table through programming. This section describes the use of the
G10 command for loading these offset tables.
Important: Only the value in the table changes when a G10 modifies a
table value. If the value just changed with a G10 is currently being used
by the control, the value of the active offset does not changed until it is
called again from the offset table using a T word.
When the control is in: any values entered in an offset table using the G10 command are:
incremental mode (G91) added to the currently existing offset values.
absolute mode (G90) replace the currently existing offset values.
Use this format to modify the offset tables with a G10:
G10 L10 P__ X__ Z__ R__ Q__ T__ O__
Where : Is :
L10 determines the table being modified.
L10 -Modifies the wheel geometry and radius offset tables
P the offset number that is having its values changed is specified with the P word. The P
word must be a 2-digit number specifying the radius/orientation offset number and/or
the wheel geometry offset number being modified.
X * the value to add to or replace the wheel length offset for the X-axis. This value can be
a diameter or radius value if using a cylindrical grinder as determined with the O word.
This value is entered into the wheel geometry offset table.
Z * the value to add to or replace the tool length offset for the Z-axis. This value is entered
into the wheel geometry offset table.
R the value to add to or replace the dresser/wheel radius compensation amount. This
value is entered into the radius offset table.
Q the value to add to or replace the dresser/wheel radius compensation orientation
value. This value is entered into the radius offset table.
O determines if the value being entered into the offset table is a radius or diameter value.
This applies only when setting data for the control’s diameter axis (typically the axis
perpendicular to the spindle) on a cylindrical grinder. If no O word is programmed, the
control uses the current radius/diameter mode active on the control.
O1-indicates a radius value
O2-indicates a diameter value
Surface grinder applications should not program an O word.
* indicates the axis name configured on your machine. This manual assumes a (ZX) 2 axis machine
configuration.
Any values not specified in the G10 block remain in the table unchanged.
13.2
Programming Changes to
Wheel Geometry and Radius
Offset Tables (G10L10)