Rockwell Automation 8520-GUM 9/Series CNC Grinder Operation and Programming Manual Documentation Set - Manual (Page 624)

Turning Operations
Chapter 18
18-8
G24 Straight Facing
The format for the G24 straight facing cycle is:
G24X__ Z__;
Where : Is :
X__ the length of grind along the X-axis. In incremental mode, specify the amount of
feed across the part. In absolute mode, specify the coordinate position of the
end point of the grinding/dressing stroke. X can be programmed as a diameter or
radius value.
Z__ the grinding/dressing depth for the Z-axis. In incremental mode, specify the
amount of infeed. In absolute mode, specify the coordinate position at the
desired grinding/dressing depth.
After the control executes the G24 block, the control re-executes the cycle
for any following block that commands axis motion until the cycle is
canceled. The values of the axis words in the following block replace the
values of the parameters specified in the original G24 block and the cycle
is re-executed using these new values.
Example 18.3
Straight Facing Cycle
G90G00X30.Z22.;
G24X10.Z15.F10.
Z13.;
Z11.;
G00;
Figure 18.7
Results of Example 18.3
Grinding/Dressing feed
Rapid feed
15
13
11
X
Z
10
Grinding
wheel
12066-I